Mirror

Mirror reflects sketch geometry across a line or an axis. Draw one half of a symmetric profile, mirror it, and the two halves join into one region.

In the viewport

1. Click Mirror on the sketch toolbar (shortcut M). The Mirror dialog opens docked on the right with a Geometry slot and a Mirror line slot.
2. Click the sketch edges to mirror. Picks accumulate as chips; click a picked edge again, or a chip's ✕, to drop it. Any edge stands for its whole primitive — one side of a rectangle picks the rectangle.
3. Click the Mirror line slot, then click a sketched line in the viewport (a guide works too), or the sketch's own X or Y axis line. An axis pick shows as the chip Sketch Y axis and is written as xAxis() / yAxis(). The reflection previews in blue, and the statement about to be written shows under the dialog.
4. Click Apply.

Double-click the mirror's row in the timeline to reopen the dialog and re-pick the geometry or the line.

By hand

mirror(line)                            // mirror everything across a sketched line
mirror(line, g1, g2, ...)               // mirror specific geometry across a line
mirror(yAxis())                         // mirror across the sketch's own Y axis
mirror(xAxis(), g1, g2, ...)            // mirror specific geometry across the sketch's X axis
mirror("y", g1, g2, ...)                // across a WORLD axis — see below

Any sketched line can be the mirror line, including a guide you do not want in the profile. Write the statement after the constraints — mirror consumes solved geometry.

The code behind it

The tool writes the datum form, mirror(yAxis(), base, side, top). On the XY plane the world axis "y" is the same line, which is what this hand-written example uses.

plate.part.js

import { bezier, extrude, line, mirror, sketch } from 'fluidcad/core';
import { coincident, horizontal, vertical, fix, distance } from "fluidcad/constraints";

// A latch plate: the right half is drawn, the left half is its mirror.
sketch("xy", () => {
    const base = line([0, 0], [40, 0]);
    const side = line([40, 0], [40, 30]);
    // The curved top, sweeping in to the tip on the axis.
    const top = bezier([40, 30], [40, 70], [10, 60], [0, 90]);
    coincident(base.end(), side.start());
    coincident(side.end(), top.start());
    horizontal(base);
    vertical(side);
    fix(base.start(), [0, 0]);
    distance(base.start(), base.end(), 40);
    distance(side.start(), side.end(), 30);
    // Mirror the half across world Y. On the XY plane world Y is the
    // sketch's own vertical, so the two halves meet on the axis and close.
    mirror("y", base, side, top)
})

extrude(4)

Sketch axes and world axes

Bare axis strings like "x" and "y" always mean world axes. On the XY plane that is also the sketch's own X and Y, but on other planes it is not:

// ✗ collapses: world Y is the front plane's normal
sketch("front", () => {
    const b = bezier([200, 200], [-120, 380], [200, 450], [0, 600])
    mirror("y", b)
})

The sketch's own axes are the datums xAxis() and yAxis() — the same fixed lines constraints target (collinear(xAxis(), l)), accepted here as the mirror axis:

The code behind it

plate.part.js

import { bezier, extrude, line, mirror, sketch, yAxis } from 'fluidcad/core';
import { coincident, horizontal, vertical, fix, distance } from "fluidcad/constraints";

// The same latch plate, drawn standing up on the front plane.
sketch("front", () => {
    const base = line([0, 0], [40, 0]);
    const side = line([40, 0], [40, 30]);
    const top = bezier([40, 30], [40, 70], [10, 60], [0, 90]);
    coincident(base.end(), side.start());
    coincident(side.end(), top.start());
    horizontal(base);
    vertical(side);
    fix(base.start(), [0, 0]);
    distance(base.start(), base.end(), 40);
    distance(side.start(), side.end(), 30);
    // On the front plane world Y is the plane normal — mirroring across it
    // would collapse the half. yAxis() is the sketch's vertical (world Z).
    mirror(yAxis(), base, side, top)
})

extrude(4)

Sketch plane	xAxis()	yAxis()
"xy" / "top"	world +X	world +Y
"xz" / "front"	world +X	world +Z
"yz" / "right"	world +Y	world +Z

The datums work with face sketches and custom plane() objects, and they are per argument — bare strings in the same call stay world-relative:

sketch("front", () => {
    copy("linear", [yAxis(), "x"], { count: 2, offset: 30 }, shape)
})

You do not need the datums when the mirror line is a sketched line (it already lies on the plane), or on sketch("xy"), where world and sketch axes agree.

For mirroring a feature rather than sketch geometry, see Patterns → Repeat; for solids, Transforms → Mirror.